This command incrementally regenerates the active part's history re-evaluating each feature.  History related modifications such as changes to dimensions, equations, feature reordering or deleting performed since the last regeneration will be incorporated into the active part.
   

The active part is cleared for regeneration.
   

• Pick repeatedly from the History Manager to step through the history feature by feature.  As each feature is regenerated it is removed from the upper list.
  
  Or
  
  If an error occurs during the regeneration of any feature select an option from the History Replay Error Menu to correct the problem.
   

 

 

Use this command to rollback the active part's history to a feature and modify it. If the feature is defined by a sketch, the history is rolled back to that sketch.  If the feature is not defined by a sketch,

such as a fillet or chamfer, the history is rolled back to the first input defining the feature.  This may be the fillet or chamfer radius. If the feature is currently suppressed, it will be unsuppressed by this command.
 

1. Select a feature to edit.  The history will regenerate and stop at the feature selected for editing.

2. Edit the feature or perform other functions using the History Manager.

3. If an error occurs during the regeneration of any feature, select an option from the History Replay Error Menu to correct the condition.

 

 

 

Use this command to quickly edit the last feature in the active part's history, if the feature corresponds to the last undoable operation.  If it is, then the feature is undone and the feature command is invoked using the original feature parameters as defaults.  If the last undo-redo transaction does not match the last feature in the history, the following message is displayed.
 

[The last operation did not create a feature.]

 

• If the last feature corresponds to the last undoable operation,enter the new parameters for the feature.
   

 

 

Use this command to rollback the active part's history to the feature just prior to a selected feature.  The selected feature can then be deleted or otherwise modified.
 

1. Select a feature to rollback to.

2. You may edit the selected feature or perform other functions with the History Manager.

3. If an error occurs during the regeneration of any feature, select an option from the History Replay Error Menu to correct the condition.
    

 

 

Use this command to replace one feature with another in the active part's history. The replacement feature "inherits" the unique id and/or label of the original feature.  This is done so that geometry attached to the original feature will attempt to reattach to the new feature during a regen.
  

1. Select the feature to replace.

2. Select the replacement feature.
    

 

 

Use this command to rename a feature.  This is the name that appears in the active part's history and on the feature's entity label.

 

 When renaming a variational component, this operation is logged in the active assembly's history.

 

1. Select the feature to rename.

2. Enter a new name for the feature.

 

 

 

Use this command to delete the history of the active part and create one feature named StartData that contains a backup of all the geometry (similar to the Backup Feature command) that existed at the time this command was executed. Future regenerations begin with the StartData feature, which simply re-initializes the part with all of the geometry backed up with the StartData feature.

 

If your part's history is large or complex and it no longer regenerates easily (or at all), you can compress the entire history into a single feature called StartData. You can then begin to add new features to a simpler, shorter history that will regenerate reliably once again. You lose the parametrics associated with the compressed data, but if the history will not regenerate, you've lost it anyway. Once you encapsulate the history, you don't have to struggle with unreliable history to get down to the more recent features.

 

• Middle-click to encapsulate the active part's history.
   

Notes

 

This command causes file sizes to grow rather than decrease!  This command does NOT to crunch down the size of a part.  The purpose of this command is to provide a way to go forward with a history that will not regen.   It captures the current state of the part and makes it the beginning point of the part's history, making it possible to regen new operations applied against the captured state.

 

After the Encapsulate command, there are two copies of geometry in the part -- 1) a backup copy and 2) a working copy.   Subsequent edits are applied to the working copy.   The backup copy is kept as the starting point for regeneration of the new history.  Because there is a backup copy and a working copy, part size roughly doubles when you use this command.  However, this command does allow you to use and work with a corrupted model that will not regen.

 

 

 

Use this command to cut (delete) selected features to the 3D clipboard. The Cut and Paste Features commands can be used to reorder features within the active parts history.

 

 

Required Inputs

 

• Entity - Select the operations to cut and then middle-click to continue.

• File/Part - You can save the current contents of the 3D clipboard.  Select a VX file and enter a name for the saved clipboard.  If there are other 3D clipboards saved for the file, you select one from the list to save to.  It will be overwritten.  To delete a saved 3D clipboard, right-click on it and pick Delete from the pop-up menu.

• Preview - Select Graphics or Attributes preview a saved 3D clipboards otherwise select Off for this option.

 

 

 

Use this command to copy selected features to the 3D clipboard. This command also copies the current graphics window image to the Windows clipboard. If you then do a "Paste" operation inside a Microsoft application, the image is pasted inside the application window.

 

If you use one of the VX "Paste" commands (e.g., Paste from 2D Clipboard or Paste Features from 3D Clipboard ), the geometry is pasted and the image is ignored. The Cut and Paste Features commands can be used to reorder groups of features within the active parts history.

 

 

Required Inputs

 

• Entity - Select the operations to copy and then middle-click to continue.

• File/Part - You can save the current contents of the 3D clipboard.  Select a VX file and enter a name for the saved clipboard.  If there are other 3D clipboards saved for the file, you select one from the list to save to.  It will be overwritten.  To delete a saved 3D clipboard, right-click on it and pick Delete from the pop-up menu.

• Preview - Select Graphics or Attributes preview a saved 3D clipboards otherwise select Off for this option.

 

 

 

Use this command to paste the current contents of the 3D clipboard into the active part's history.  Features located in the 3D clipboard can be pasted in the middle of the Step through Part History command.  If the clipboard feature is a sketch, a Relocate replay operation is automatically invoked. The Cut and Paste Features commands can be used to reorder features within the active parts history.
 

• Middle-click the mouse to accept the pasted features.

• Use the History Manager to locate the pasted feature in the history of the active part.

 

 

 

Optional Inputs

 

• File/Part - If you have saved 3D clipboards you can select one to paste instead of pasting the active 3D clipboard.  Select a VX file that contains saved 3D clipboards and then select a 3D clipboard from the list.  You can middle-click or pick OK from the command options from to paste the operations.  To delete a saved 3D clipboard, right-click on it and pick Delete from the pop-up menu.

• Preview - Select Graphics or Attributes preview a saved 3D clipboards otherwise select Off for this option.

 

 

 

Use this command to delete features from the active part's history. Use the Erase Entities command to delete historically-generated entities.  Refer to the note below about deleting components using this command from the Assembly Manager.

  

• Select the feature(s) to delete or select Delete from one of the Object Editor menus listed above to delete the highlighted feature.

 

 

 

• Regen History Incrementally after Editing (see CAD Tips & Techniques).

• Use Caution when Replacing a Feature (see CAD Tips & Techniques).

• About Patterning and Mirroring Components (see CAD Tips & Techniques).
   

• When you Redefine a history operation that is dependent on layer visibility, the layer visibility status saved with the operation is restored before you are given the opportunity to redefine the input parameters for the operation.  At that point, you can display the Layer Manager by selecting Tools>Layer Manager... and modify the layer visibility status.  The new status will be used to re-evaluate entities gathered with any Pick All operations and will be saved with the operation, replacing the old layer visibility status saved with the operation.
   

• You can use this command from the Assembly Manager to delete components in the active assembly that reside in the active file or another file.  An error message is displayed if you try to delete a patterned or mirrored component.  You can delete a component inserted directly in the history -- but not a component generated by a history operation (e.g. pattern or mirror).  In this case, you have to activate the component's parent part and then use the Erase Entities command to delete the patterned or mirrored component.