When the prompt line reads Start canned cycle, click Edit to display the Start Drill dialog box.
.
Feed Rate
Specify the feed (plunge) rate for the drill.
Initial Rapid
For 2 Axis and 3 Axis Drill, this is the absolute Z plane for the beginning of the drill cycle. The default value is determined from the highest visible geometry and adding the rapid plane clearance from the options page.
For 4 Axis and 5 Axis Drill, this is relative to the selected geometry. The default value is determined from the options page.
Plunge Clearance
This is the relative distance above the top of the hole at which the tool should start moving at feed rate. The tool will move at rapid speed from the Initial rapid plane to the Plunge Clearance point.
Retract To
This is the level to which the drill will retract at the end of the drill cycle.
Rapid Plane
This is a G98 type move using the value entered for Initial Rapid.
Plunge Clearance
This is a G99 type move using the value entered for Plunge Clearance.
Dwell Time
Enter the length of time to dwell for the appropriate cycle. This time is entered in milliseconds (1000 = 1 second).
Cycle Type
Drill
Straight drilling: feeds down to bottom Z then rapids out (G81 on most machines).
Peck
Standard peck drilling. The peck increment is described below (G83 on most machines).
Tap
Access a standard tapping cycle that feeds down, then reverses the spindle at the bottom of the hole and feeds up (G84 on most machines).
Tapping requires the feed rate to match the spindle speed. SURFCAM can do this automatically. Set the tapping tools in the drill library with 1 flute. Set the chip load to the lead value of the tap. A 1/4-20 tap would have a chip load value of 0.05.
Left tap
Access a Left-handed tapping cycle that operates exactly like the Tap cycle with reversed spindle direction.
Rigid tap
Access a tapping cycle for tap that is held directly in the spindle. The machine controller synchronizes spindle speed and feed rate.
Rigid left tap
Access a Left-handed tapping cycle that operates exactly like the rigid tap cycle with reversed spindle direction.
Ream
Similar to the Drill cycle, but this will cause the tool to FEED out of the hole instead of a rapid move out and is usually used with a reamer (G85 on most machines).
Bore
This is a fine boring cycle that will bore to the bottom of the hole. The spindle will stop and orient. The tool is then moved away from the edge of the hole a small distance. The tool will then rapid out of the hole (G86 on most machines).
Back bore
This is a back-boring cycle that will stop and orient the spindle before the cycle starts. The tool rapids to the bottom of the hole, and feeds toward the wall before starting the spindle. The tool will then feed up to the top of the hole, boring the hole from the bottom up.
Countersink
This creates a countersink on a previously drilled hole.
Peck Increment
Enter the peck increment for the peck cycle.
Bore Side Clearance
This is the side clearance for the bore cycles.