When you run INC2APT, the Convert INC To APT File dialog box will be displayed.
Note: Command line options, as described below, are indicated in red.
-d is an additional command line option specifying that the dialog box be displayed. If you do not want this default, delete the -d in command lines containing INC2APT in the PST file. Then use the -d in a command line when you do want it displayed.
-I Input INC File
Enter the name of the INC file to be converted or click the Browse button to display the Open dialog box from which to select an INC file. If you enter a file name in an operating system that supports long file names, enclose a file name containing spaces in double quotes.
-O Output APT File
Enter the name for the APT file that will be produced.
-F Feed Angle Limit
This tells INC2APT to break the feed move for 4 or 5 Axis machines if the change in the tool axis vector exceeds this value. The default value is 360.
-R Rapid Angle Limit
This tells INC2APT to break the rapid move for 4 or 5 Axis machines if the change in the tool axis vector exceeds this value. The default value is 360.
-W Output World Coordinates
Check this box if the world coordinate system is to be used to output values to the APT file. Normally the machine coordinate system in the INC file is used to output values. These coordinate systems, however, can be the same.
If the -W and -EVENT boxes are both checked, the tool vectors (I, J and K ) are added to the APT commands. See EVENT.
-M Invert LCS (forces a - W too)
Check this box to invert the Local Coordinate System—invert the CView coordinate vectors.
-5 Output Tool Axis Vectors
Check this box to output 5-Axis tool vectors, even if the INC file was not done in 5-Axis.
If the -5 and -EVENT boxes are both checked, the tool vectors (I, J and K ) are added to the APT commands. See EVENT.
-OP Output Operation Information
Check this box to add the command OPERTN/ n1, n2, n3 as a line in the APT file. The first value, n1, is the Operation Type—for example, Turn = 1, Pocket = 6, and 3 Axis Cut = 9.
The second value, n2, is the Cycle Type—for example, Drill = 0, Left Tap = 6, and Rigid Tap = 13. If the operation is not a cycle, n2 will be set to –1.
Th third value, n3, is the Spindle Type for mill/turn operations—Main Spindle = 0 and Sub Spindle = 1. If the operation is not a mill/turn operation, n3 will equal –1.
List of all values for OPERTN/ n1, n2, n3.
-P Output Next Tool Pre-select
Check this box to cause INC2APT to search ahead in the INC file for the next tool number when it encounters a tool change command. INC2APT will then insert, into the APT code, a tool load command—LOADTL/ n (n = current tool number)—followed by a tool select command—SELCTL/ n (n = next tool number).
-B Output ROW/START, ROW/END
Check this box to output a ROW/START command when a "Start of row" is found in the INC file and a ROW/END command when an "End of row" is found.
-TOOLINFO Output Tool Information
Check this box to output tool description comments.
-X Insert Move When Vector Crosses Quadrant
Check this box to output an extra move (a GOTO) when the XY of the normal vector crosses a quadrant (0, 90, 180, 270 degrees) and insert a "QUAD" line above it.
-C Check and Warn if Output File Exists
Check this box to cause INC2APT to determine if the target APT file already exists and display a warning if it does.
-FAR Force Feedrate After Each Rapid
Check this box to insert a redundant Feed command above a GOTO that follows a rapid GOTO command. (A GOTO command that follows another GOTO that was preceded by a Rapid command is automatically a Feed command.)
-N Output RAPID0/RAPID1 Format
Check this box to replace Rapid/GOTO sequences with modal Rapid0/Rapid1 commands, similar to FANUC G0 and G1 commands. This produces a smaller APT file if the post processor supports this format.
-CVIEW Output CVIEW Number and Name
Check this box to output the CVIEW Number and Name.
-EVENT Output Event Data
Check this box to display the APT file tool motion commands. When a tool motion event is found in the INC file, INC2APT displays the correct APT command. The current location of the tool follows the APT command name. If either the -W or -5 boxes are checked the tool axis vectors (I, J and K) follow the tool location.
APT commands that identify the start of a tool motion are placed before the GOTO command or the group of commands that control the tool motion.
APT commands that identify the end of a tool motion are placed after the GOTO command or the group of commands that control the tool motion.
-Debug Output Debug Data
Check this box to display an APT comment string when an INC record is found that INC2APT cannot identify. The record number and the record size are displayed.
Example - $$ Unrecognized INC record #221, Size 190
Decimal Precision
-Precision <decimal digits>
Specify the number of decimal places to output floating point numbers. This is used for locations and dimensions.
Vector Precision
-VPrecision <decimal digits>
Specify the number of decimal places for floating point numbers. Usually, this should be a higher precision than for locations and dimensions so that the vector maintains its unit length.
See also Technical Information.