is created and added to the FeatureManager design tree.
The software also creates two default configurations
in the ConfigurationManager: a parent configuration Default<As
Machined> and a derived configuration Default<As
Welded>.When you create the first structural
member in a part, a weldment
feature
is created and added to the FeatureManager design tree.
The software also creates two default configurations
in the ConfigurationManager: a parent configuration Default<As
Machined> and a derived configuration Default<As
Welded>.
All structural members include the following attributes:
Structural members use profiles, for example an angle iron.
Profiles are identified by Standard, Type, and Size.
Structural members can include multiple segments, but all segments can use only one profile.
Multiple structural members, each with a different profile, can belong to the same weldment part.
Within a structural member, only two bodies can intersect at any particular point.
Structural members appear in the FeatureManager
design tree as Structural Member1,
Structural Member2, and so on.
Bodies created by the structural members appear under Solid
Bodies 
.
You can create your own profiles (Type, Size, and Standard), and add them to the existing library of weldment profiles.
Weldment profiles are located in: <install_ dir>\data\weldment profiles.
Structural members allow you to specify the pierce point of the profile, relative to the sketch segment used to create the structural member.
You can select structural members under Solid Bodies , and create
cut lists
used in drawings.
To add structural members:
Create a sketch.
Using linear or curved sketch
entities, you can create multiple 2D sketches with planes, create a 3D
sketch, or combine 2D and 3D sketches.
Click Structural
Member 
(Weldments toolbar) or Insert,
Weldments, Structural
Member.
To add multiple structural
members, in the PropertyManager, click 
.
In the PropertyManager, under Selections, set the following options:
Standard. Select iso, ansi inch, or a custom standard that you previously defined.
Type. Select a Profile Type, such as angle iron or square tube.
Size. Select a Profile, such as 20 x 20 x 3.
Path segments. Select a set of sketch entities in the graphics area.
Merge arc segment bodies. (For curved entities only.) Select to merge arc segment bodies with adjacent bodies in the structural member. Clear to create a separate body for each curved entity. The arc segment and adjacent bodies must be tangent in order to merge.
As you select the structural members, Settings appears. Under Settings you can:
Apply a corner treatment,
or clear Apply corner treatment
to specify a corner treatment later. For example, you can apply the corner
treatment when you trim
the structural members.
You can also modify the corner treatment, allowing you to specify multiple
corner treatments per structural member.
Change Rotation
Angle 
so that the structural member turns by a
set number of degrees relative to the adjacent structural member.
Click Locate Profile to change the pierce point between the adjacent structural members. The default pierce point is the sketch origin.
Click 
.
This clears Path segments, and allows you to apply additional, consecutive structural members.
Select the second set of structural members. If necessary, you can apply a different Standard, Type, and Size.
Click to clear the Path
segments, and to create additional structural members.
