This cycle fills a rectangle with cuts spaced at the specified 'Cut Increment'.
One corner is the current position of the tool. Alternatively you can check 'Digitise Start' (see below) and digitise both corners.
You can use the cycle to face off the part, for example.
Note that for entity digitises, the location is not associative to the entity (it will not automatically update if you move the entity).
Feedrate - Specifies the feed movement speed of the tool. This is feed per minute, or feed per revolution (default), as selected using the Feed Type (M-Functions menu) command.
Speed - Specifies the spindle speed of the turning centre in revolutions per minute . If you have previously selected Constant Surface Speed using the CSS (M-Functions) command, this spindle speed is measured in surface speed (metres or feet) per minute.
Cut Increment - Specifies the distance between cuts in the units used for the part.
% Stepover - Specifies the distance between cuts as a percentage of the effective length of the cutting edge of the tool. Use only ONE of these parameters to define this distance. This will then be modified by default (see No Stepover Adjustment below).
No Stepover Adjustment - Once the cut increment has been defined, by default EdgeCAM ensures that a small cut is not made on the last pass by averaging the cut distance between all the passes. To stop EdgeCAM from averaging the cuts, check the No Stepover Adjustment box.
Link Type - Selects the rate to move the tool at between drives. This can be at the Rapid or Feed rate.
Canned Cycle - Check to use the machine tool controller's canned cycle instead of the CNC code generated by EdgeCAM for the turning cycle.
Safe Approach - Check to use the Safe Approach strategy on the initial approach move. This causes approach moves to be split into two separate blocks. If a radially mounted tool is in use the approach will be in the order Z and then X. For an axially mounted tool the order will be X and then Z.
Rough Cuts Only - Check to rapid move the tool back for the next drive. If the Rough Cuts Only box is blank, the tool feeds along the profile and to the previous drive line before returning for the next drive.
Digitise Start - Check to select a cycle start position when entering co-ordinate data for the cycle.
Feature Name - Enter a name here to allow labelling of digitised information for this cycle to enable "pickup" of this information in another (similar) cycle.
Chipbreak - Distance for chipbreak action - Code Generator dependent.