Rationalise dialog

www.kxcad.net Home > CAM Index > EdgeCAM Index >



Only available in the milling environment.

Use this dialog to create a new sequence containing re-ordered instructions from the active sequence. You might want to re-order the sequence so that all the roughing instructions appear above the finishing instructions, for example.

Strategy

Choose how you want the sequence to be re-ordered:

 

By Tool

 

Re-orders the sequence based on toolchange instructions. Instructions are moved in blocks that start with a toolchange instruction and extend to the instruction before the next toolchange.

  1. The toolchanges (along with their 'block') are placed in order of their Sort Priority value. The lowest value is placed highest up the sequence. A blank value is treated '0'. If tools have the same Sort Priority, the sort on priority will group them together and their order within the group will be determined by their original (pre-rationalise) order. (See more on Using Sort Priority when Inserting and Merging Sequences...)

  2. All the repeat toolchange instructions (that is toolchanges back to the same tool) are then deleted. To be the 'same tool', all the toolchange parameters must match ('Turret Position', 'Diameter', 'Offset' and so on), as well as the Sort Priority setting.

See a warning.

 

By CPL

Reduces index moves by grouping together instructions that have:

  • The same rotary axis positions (as specified by Move menu ► Index). Any necessary retracts to safe distance are kept/inserted before the indexes.

  • The same Datum (as specified by Move menu ► Index and/or M-Functions menu ► Datum Shift).

 

By Index

This produces the same result as 'By CPL' above, except that the instructions' Datum is not taken into account.

Merge Hole Cycles

(Only available if with Strategy set to 'By Tool' and the code generator supports multilevel/depth). Check this for the separate Hole cycles under a toolchange to be merged into one Hole cycle that machines all the holes.

See these notes and conditions.

Safe Clearance

Retracts to a safe clearance height may be inserted; before inserted index and datum shift instructions for example.

For these moves, specify how the safe Z value is to be derived:

 

Toolchange Z

The 'Z Change' parameter, as set in the Machine Parameters dialog, Tool Change tab.

 

Max Clearance

The maximum 'Clearance' value (as found in a Roughing cycle's Depth tab, for example) of any of the instructions that are moved.

 

Z Initial

The 'Initial Plane' parameter, as set in the Machine Parameters dialog, General tab.