|
Reserved Word |
Definition |
|
<ABS-DEPTH> |
Absolute Z axis depth from Z axis origin, <ZSURF> <DEPTH>. |
|
<ABS-SHIFTX> |
X offset from machine zero to current setup without any rotations applied. |
|
<ABS-SHIFTY> |
Y offset from machine zero to current setup without any rotations applied. |
|
<ABS-SHIFTZ> |
Z offset from machine zero to current setup without any rotations applied. |
|
<ABS-STEP1> |
Absolute first step, <ZSURF> <STEP1>. |
|
<ABS-ZCLEAR> |
Absolute position of Z Clear -- Z Clear + Z Surf (not used in incremental programming). |
|
<ABS-ZRAPID> |
Absolute position of Z Rapid -- Z Rapid + Z Surf (not used in incremental programming). |
|
<ANG-CFEED> |
Outputs the feed value required for an Okuma or Fanuc control to maintain the programmed feed rate. This is a Cartesian feed rate value. |
|
<ANG-DPM> |
Wrapped feed rate, degrees per minute. |
|
<ANG-FPM> |
Wrapped feed rate, inch (or mm) per minute. |
|
<ANG-INVTIME> |
Wrapped feed rate inverse time. |
|
<ARC-X> |
Used in the circular interpolation block to specify the signed X distance from the start point of the arc, to the center of the arc along the X axis. |
|
<ARC-Y> |
Used in the circular interpolation block to specify the signed Y distance from the start point of the arc, to the center of the arc along the Y axis. |
|
<ARC-Z> |
Used in the circular interpolation block to specify the signed Z distance from the start point of the arc, to the center of the arc along the Z axis. |
|
<BOT-LALLOW> |
Corresponds to Bottom Semi Finish Allowance or Bottom Semi Finish Allowance attributes for a milling operation. |
|
<COMP-NUM> |
Compensation number passed from FeatureCAM. |
|
<COMP-VAL> |
Cutter compensation diameter. |
|
<DEPTH> |
Z Depth value passed from FeatureCAM for drilling-type cycles. |
|
<DWELL> |
Reproduces the dwell value passed from FeatureCAM. |
|
<EXP-LENGTH> |
Corresponds to the Exposed length tool parameter. |
|
<FEED> |
Feed rate value identifier passed from FeatureCAM. |
|
<FINI-ALLOW> |
Finish allowance of a milling operation. |
|
<FIXTURE> |
Fixture ID number passed from FeatureCAM. |
|
<FSHIFTX> |
The X distance from the fixture offset to the local coordinate system. |
|
<FSHIFTX> |
The Y distance from the fixture offset to the local coordinate system. |
|
<FSHIFTX> |
The Z distance from the fixture offset to the local coordinate system. |
|
<HELIX-PITCH> |
Pitch of helical move. Controlled by Max Ramp Angle attribute. |
|
<INC-DEPTH> |
Incremental depth from Z Clear, <DEPTH> + <ZCLEAR>. |
|
<INC-MACX> |
X location of the pattern instance that will be cut by the macro. This coordinate is typically not output in the cnc program. |
|
<INC-MACY> |
Y location of the pattern instance that will be cut by the macro. This coordinate is typically not output in the cnc program. |
|
<INC-MACZ> |
Z location of the pattern instance that will be cut by the macro. This coordinate is typically not output in the cnc program. |
|
<INC-STEP1> |
Incremental first step, <STEP1> + <ZCLEAR>. |
|
<MACRO#> |
Macro number identifier (system-generated). Macros are not user definable, however some Macros are generated automatically, especially with multiple fixture parts and for repeated features. This number starts at 00 and increments automatically up to the Max Macros number that is contained on the General Information dialog box. |
|
<MIN-STEP> |
Minimum Peck drilling parameter. |
|
<NO-DRAG-X> |
Amount to move over in X for no drag boring. |
|
<NO-DRAG-Y> |
Amount to move over in Y for no drag boring. |
|
<NEXT-TL> |
Represents the next tool to be used (may be required by some controls). |
|
<NOSE-RAD> |
Tool nose radius of an endmill or the tip radius of a threading tool or turning tool. |
|
<OFFSET#> |
Diameter offset register number passed from tool mapping dialog. |
|
<OV-LENGTH> |
The overall length of the tool. Corresponds to the Overall Length parameter of a tool. |
|
<PITCH> |
The pitch value for the Tap cycle. This value is in Z-distance per spindle revolution. |
|
<RADIUS> |
Reproduces arc radius in a circular block. |
|
<ROT1-ANSI> |
Rotation about primary axis in ANSI style. |
|
<ROT1-MATH> |
Rotation about primary axis in Mathematical style. |
|
<ROT1-WIND> |
Rotation about primary axis in Winding style. |
|
<ROT2-ANSI> |
Rotation about secondary axis in ANSI style. |
|
<ROT2-MATH> |
Rotation about secondary axis in Mathematical style. |
|
<ROT2-WIND> |
Rotation about secondary axis in Winding style. |
|
<S-RAD> |
Generates the signed arc radius value in a circular block, +R<180 degrees and R>180 degrees.
|
|
<SEQ> |
This is a line sequence number identifier (when the word appears in a line, it is substituted with the current sequence number, and is subsequently incremented by the sequence step value). |
|
<SHIFTX> |
X offset from machine zero to current setup after axis rotations are applied. |
|
<SHIFTY> |
Y offset from machine zero to current setup after axis rotations are applied. |
|
<SHIFTZ> |
Z offset from machine zero to current setup after axis rotations are applied. |
|
<SIDE-LALLOW> |
Corresponds to Bottom Finish Allowance or Bottom Finish Allowance attributes for a milling operation. |
|
<SPEED> |
Spindle speed value passed from FeatureCAM. |
|
<STATR-ANG> |
Initial angle of helical move. Added for Heidenhain control. |
|
<STEP1> |
First Peck value passed from FeatureCAM. |
|
<STEP2> |
Second Peck value passed from FeatureCAM. |
|
<STEPOVER> |
Step over distance passed from feature properties dialog. |
|
<TOOL> |
Tool number passed from FeatureCAM. |
|
<TOOL-DIAM> |
Tool diameter, passed from FeatureCAM. |
|
<TOOL_LENGTH> |
Cutter length of the tool. |
|
<TOOL-LENGTH> |
Corresponds to cutter length of endmills or length of drills. |
|
<TOTAL-ANG> |
Total angle of a helical move. Added for Heidenhain. |
|
<TPI-PITCH> |
The TPI value for the Tap cycle in an inch CNC file or the pitch value for the Tap cycle in a millimeter CNC file. |
|
<X-CEN> |
Reproduces the absolute X coordinate position from the X axis origin to the arc's center in a circular block |
|
<X-CHANGE> |
X coordinate of desired tool change location passed from post options dialog. |
|
<X-COORD> |
Current X coordinate position. |
|
<X-VECTOR> |
Calculated X vector for the next move (cutter compensation vector for Cincinnati Milacron). |
|
<Y-CEN> |
Reproduces the absolute Y coordinate position from the Y axis origin to the arc's center in a circular block. |
|
<Y-CHANGE> |
Y coordinate of desired tool change location passed from Post options dialog. |
|
<Y-COORD> |
Current Y coordinate position. |
|
<Y-VECTOR> |
Calculated Y vector for the next move (cutter compensation vector for Cincinnati Milacron). |
|
<ZCEN> |
Reproduces the absolute Z coordinate position from the Z axis origin to the arc's center in a circular block. |
|
<Z-CHANGE> |
Z coordinate of desired tool change location passed from post options dialog. |
|
<ZCLEAR> |
Z coordinate that programmed feed rate begins. This is the Plunge Clearance attribute passed from hole properties dialog. |
|
<Z-COORD> |
Current Z coordinate position. |
|
<Z-INC> |
Rough pass Z increment attribute passed from feature properties dialog. |
|
<Z-INDEX-CLR> |
The Z retract distance when indexing 4th axis. |
|
<ZRAPID> |
Z distance from surface of stock that tool rapids to. This distance is the Z rapid plane attribute plus the absolute distance from the UCS to the surface of the stock. |
|
<ZSURF> |
Z coordinate of stock surface relative to UCS origin. |