Blocks and their Toolpath Variables

	CUT_FILE	SET_ON this flag will divide the G-code file.
	BLOCK_NUM	The current block number as appears in the TP_LIST.
	DBL_QUOTE	The character: "

AXIS_NUM

The number of sets of axes (coordinate systems) used in the current procedure.

	ANGLE_INCR	All relevant procedures - Parallel - angle increment. Procedures: CLEANUP, SRFPKT, ZCUT.
	BET_LAYERS	Between layers = 1 Not between layers = 0 Procedures: WCUT.
	BY_SCALLOP	BY SCALLOP = 1 BY 2D SIDE STEP = 0 Procedures: (Parallel cut): CLEANUP, SRFPKT, WCUT (between layers).
	CHECK_OFST	Offset of the check surfaces. Procedures: CLEANUP, 3D_STEP, PLUNGE_MILL, SRFPKT, SRFPRF, SURCLR, SURMILL, WCUT, ZCUT.
	CHECK_TOL	Tolerance of the check surfaces. Procedures: CLEANUP, 3D_STEP, PLUNGE_MILL, SRFPKT, SRFPRF, SURCLR, SURMILL, WCUT, ZCUT.
	CIR_INTERP	Circular interpolation code. - Set by user. On by default. On = Circular interpolation. Off = Linear interpolation.
	CONT_OFST	Offset of the 1st contour. Procedures: CLEANUP, 3D_STEP, POCKET, PROFILE, PLUNGE_MILL, SRFPKT, SRFPRF, WCUT, ZCUT.
	CONT_TOL	Tolerance of the contours. Procedures: ROUGH_5X, CLEANUP, CURVE_MX, POCKET, PROFILE, RULED_MX, SRFPKT, SRFPRF, SURCLR, WCUT, ZCUT.
	DEL_Z_UP	The DEL Z UP procedure. Procedures: CLEANUP, CURVE_MX, 3D_STEP, POCKET, PROFILE, RULED_MX, SRFPKT, SRFPRF, SURCLR, SURMILL, WCUT, ZCUT.
	DOWN_STEP	The procedure DOWN STEP value. Procedures: CLEANUP, CURVE_MX, POCKET, PROFILE, PLUNGE_MILL, RULED_MX, WCUT, ZCUT.
	END_ANGLE	All relevant procedures - Parallel - end angle. Procedures: CLEANUP, SRFPKT, ZCUT.
	I_START J_START K_START	I, J and K components of the vector which, in wire-EDM machining and 5X milling, describes the initial direction of the tool axis.
	LEAD_ANGLE	All relevant procedures - leading angle. Procedures: SURCLR, SURMILL.
	MILL_ANGLE	All relevant procedures - Parallel - milling angle. Procedures: (only when Radial cut is not used): CLEANUP, PLUNGE_MILL, SRFPKT, WCUT, ZCUT.
	MIN_CLRLN	<value> = Minimum Clear Length (if relevant) -1 = Applicable, but not calculated (for any reason). For example, if the following values are set for the parameter Limit Machining by Tool Holder: Yes, No. Ignore Holder, or No. Calc. Minimum - but the procedure is not updated (ex: stock). -2 = Not supported. Procedures: Rough Parallel, Rough Spiral, ReRough, Finish Mill All, Finish Mill By Limit Angle, Finish Horiz. Planar Areas, Cleanup and Pencil.
	MOVMNT_NUM	Number of movement blocks in the current procedure (not correct while using subroutines, quadrants and linear approximation to circles).
	NUM_CONT	All Relevant Procedures - Number of contours.
	NUM_CSRF	All Relevant Procedures - Number of Check surfaces.
	NUM_LAYERS	Number of layers in the procedures. Mill motions only. 0 = no layers.
	NUM_P2SRF	All Relevant Procedures - Number of Part2 surfaces.
	NUM_PASS	Num of passes. Procedures: ROUGH_5X, CLEANUP, CURVE_MX, RULED_MX, SURCLR, SURMILL.
	NUM_PSRF	All Relevant Procedures - Number of Part surfaces.
	NUM_SPRING	Number of spring passes.
	ORBIT_OFS	Orbit Offset. Procedures: WCUT.
	OSIDE_STEP	Between layers / Side Step. Procedures: WCUT.
	PART_OFST	Part Surface Offset. Procedures: ROUGH_5X, CLEANUP, CURVE_MX, 3D_STEP, PLUNGE_MILL, RULED_MX, SRFPKT, SRFPRF, SURCLR, SURMILL, WCUT, ZCUT.
	PART_TOL	Part Surface Tolerance. Procedures: ROUGH_5X, CLEANUP, 3D_STEP, PLUNGE_MILL, RULED_MX, SRFPKT, SRFPRF, SURCLR, SURMILL, WCUT, ZCUT.
	PLATFORM_	Platform type: DOS, NT, SUN, SGI, HP.
	PRC_UCSN1...13	Procedure UCS name (256 characters).
	PROC_CMNT	The procedure comment.
	PROC_NAME	The name of the current procedure (e.g. PROFILE, DRILL).
	PROC_NUM	The procedure number created by the system when the procedure was first defined (This number cannot be modified by the user. In each TOOL PATH the PROC_NUM is re-initialized).
	PROC_SCLP	All Relevant Procedures - Scallop. Procedures: CLEANUP, CURVE_MX, RULED_MX, SRFPKT, SURCLR, SURMILL, 3D_STEP.
	PROC_TRJ	All Relevant Procedures - Parallel/Spiral/Radial. Procedures: POCKET, CLEANUP, PLUNGE_MILL, SRFPKT, WCUT, ZCUT.
	RGH_FIN	Rough Only = 1 Rough + Finish = 2 Finish Only = 3 Procedures: CLEANUP, POCKET, SRFPKT, WCUT.
	SIDE_STEP	The procedure SIDE STEP value. Procedures: CLEANUP, CURVE_MX, POCKET, PLUNGE_MILL, SRFPKT, SURCLR, SURMILL, WCUT, ZCUT, PROFILE, SRFPRF, 3D_STEP.
	START_ANGL	All relevant procedures - Parallel - start angle. Procedures: (Radial cut): CLEANUP, SRFPKT, WCUT, ZCUT.
	STARTS_NUM	Total number of starts. Lathe/Thread tool motions only.
	STK_WIDTH	PROFILE - Stock Width. Procedures: PROFILE, SRFPRF.
	TILT_ANGLE	All relevant procedures - tilting angle. Procedures: SURCLR, SURMILL.
	TRANSF_NUM	The number of transformations.
	UNIBI_DIR	Unidir/Bidir. Procedures: ROUGH_5X, CLEANUP, CURVE_MX, POCKET, PROFILE, PLUNGE_MILL, RULED_MX, SRFPKT, SRFPRF, SURCLR, SURMILL, WCUT, ZCUT.
	WITH_STOCK	With/Without Stock. Procedures: WCUT.
	X_INTER Y_INTER Z_INTER	X, Y, and Z intermediate points.
	X_START Y_START Z_START	Current (Start) position in the original Tool Path coordinate system.
	Z_DOWN	The procedure Z DOWN value. Procedures: POCKET, PROFILE, PLUNGE_MILL, WCUT, ZCUT.
	Z_UP	The procedure Z UP value. Procedures: POCKET, PROFILE, PLUNGE_MILL, RULED_MX, WCUT, ZCUT.

	CURR_ORIG	Number of origin on NC controller to which the current origin corresponds.
	DATE_SDD	Current date: day.
	DATE_SMM	Current date: month.
	DATE_SYY	Current date: year.
	EXT_POST	Internal / external post.
	FACTOR_	The FACTOR variable in the DFPOST.
	IMS_PRJN1...13	IMS project path (256 characters). IMS Post parameters.
	I_ORIGIN J_ORIGIN K_ORIGIN	I, J and K components of the vector which, in WireEDM and 5X milling, describes the orientation of the active coordinate system in the original Tool Path coordinate system.
	MACSYS_NAM	The MACSYS name.
	NODE_ID	The workstation Node_ID.
	NUM_ORIGS	Number of origins (coordinate systems) used in all the toolpaths.
	PART_NAME	The name of the part.
	PART_NAM2...13	Part name (256 characters).
	PART_PATH	Path name- Just the path, without the name itself. Characters 1-20.
	PART_PATH2	Path name - characters 21-40.
	PART_PATH3	Path name - characters 41-60.
	PART_PATH4...13	Path name (256 characters).
	PFM_UNITS	The PFM units.
	PLATFORM_	The platform in use.
	POST_NAME	Current Post Processor name.
	TIME_SHH	Current time: hour.
	TIME_SMM	Current time: minute.
	TIME_SSS	Current time: second.
	USER_NAME	Give the user name as an output.
	X_HOME Y_HOME Z_HOME	Home position in the active coordinate system.
	X_MACH Y_MACH Z_MACH	The machine zero as was input during the POSTPR interaction.
	X_ORIGIN Y_ORIGIN Z_ORIGIN	Origin of active coordinate system in the original toolpath coordinate system.

	TP_CMNT	Toolpath comment.
	TP_CMNT2...4	Toolpath comment (256 characters).
	TP_NAME	The toolpath name.
	TP_TYPE	Toolpath main type: MILL, LATHE, WIRE, PUNCH.
	TP1_TYPE	Toolpath sub-type.
	TPNM_LOWER	Toolpath name in lowercase letters.

	CIRC_MOV	Circular movement code set in section 8, question 1 - clockwise question 2 - counterclockwise.
	ABS_ANG	(ST_ANG + ARC_ANG).
	ARC_ANG	Delta angle in degrees.
	ARC_PLN	Plane of arc block: XY = 1, XZ = 2, YZ = 3.
	CIRC_APPRX	Circular movement code: The flag -nc_circ_approx is used = 1, Otherwise = 0.
	CIRC_TOL	Controls tolerance of linear approximation of circles (overwrites value that appears in DFSTRD).
	END_ANG	End angle in degrees, between 0 and 360. ( 0 < END_ANG < 360.0).
	RADIUS_	Radius of the arc.
	ST_ANG	Start angle in degrees.
	X_CENTER Y_CENTER Z_CENTER	Center in the active coordinate system.
	X_CURPOS Y_CURPOS Z_CURPOS	Current position in the active coordinate system.
	X_ENDPT Y_ENDPT Z_ENDPT	Endpoint in the active coordinate system.

MCH_COOL

Coolant codes. - Set by section 6, questions 4, 5, 6, & 7.

	CUT_SPEED	The velocity of the cutting (Vc).
	SPIN_DIR	Spin direction code. - Set by section 6, question 1 - clockwise, question 2 - counterclockwise, question 3 - stop.

	CUTCOM_OFF	Cutter compensation off code. - Set by section 8, question 9.
	CUTCOM_ON	Cutter compensation on code - Set by section 8, question 10 - left, question 11 - right.

	CYC_2PLN	Not in use.
	CYC_CLEAR	Cycle clear-coordinate of Z on clearance plane.
	CYC_CODE	Cycle code. - Set in section 9.
	CYC_DEPTH	Cycle depth coordinate value.
	CYC_DWELL	Cycle dwell time in hundredths of a second.
	CYC_DZINIT	The DRILL procedure DEL INIT value.
	CYC_PECK	Cycle PECK value.
	CYC_REDUC	Cycle DECREASE value.
	CYC_RETR	Cycle retract code.
	CYC_TIMES	Number of times to peck.
	CYC_XSHFT	Cycle shift along the X axis.
	CYC_YSHFT	Cycle shift along the Y axis.
	CYCLE_1..12	Number of active cycles.

MCH_DWELL

Dwell value in hundredths of a second.

	N_FED_TIME	Procedure feed time.
	N_FST_TIME	Procedure rapid time.
	N_GEN_TIME	Procedure general time.

END OF TAPE: